Snap hooks, side connector openings, internal threads and barbs are what make a plastic part work. They are also what make a mold expensive. Each of them is an undercut: a feature that stops the part from coming straight out of a simple two-plate mold, so the tool needs extra moving steel to form it and then get out of the way.

The short answer: an undercut is any feature that blocks straight ejection along the mold’s opening direction. The mold releases it with a slide (side action), a lifter, a collapsible or unscrewing core, or by flexing the plastic off it. Each mechanism adds machining, fitting, maintenance and risk, so the cheapest undercut is the one a DFM review removes before the tool is designed.

What is an undercut in injection molding?

A basic injection mold has two halves, the cavity and the core, that separate along one axis, called the pull direction. A feature is an undercut when steel would have to pass through plastic to let the part out along that axis. Typical undercuts on a product enclosure:

  • Side holes, slots and connector openings in walls that run parallel to the pull.
  • Snap-fit hooks and latches that catch on the inside or outside of a wall.
  • Internal and external threads.
  • Barbs on hose fittings and retention lips.
  • Recessed or raised logos and pockets on side walls.

Undercuts are not a design mistake. Most of them exist for assembly or function. The question for each one is whether it needs moving steel, or whether a small change in the part lets a straight-pull mold form it.

Why undercuts drive mold cost and risk

  • More steel and more parts. Each action needs its own machined components, guides and wear surfaces, and each slide needs a lock that holds it shut under injection pressure.
  • A bigger, longer build. Slides need room to travel, which can push the tool into a larger mold base, and every action adds machining, fitting and tryout time to the mold tooling schedule.
  • Maintenance. Sliding steel wears. Actions need cleaning, lubrication and periodic inspection, and they are a common place for a tired mold to start flashing.
  • Cosmetic marks. Most actions leave a witness line where they meet the cavity, so slide and lifter placement has to be agreed with the cosmetic surfaces.
  • Tolerance stack. Features formed by a moving component can vary more than features cut into fixed steel, which matters for tight tolerances on connector openings.

Undercuts are one of the main reasons two molds for parts of the same size can be quoted far apart. Our injection molding price guide breaks down the other cost drivers.

How a mold releases an undercut

There are seven common ways to deal with an undercut. The first four are mechanisms built into the mold; the last three avoid side actions.

MethodWhat it formsHow it movesBest fitTrade-off
Slide (side action)Side holes, connector openings, external clips, barbsMoves sideways, driven by an angle pin as the mold opens or by a hydraulic cylinderExternal undercuts on walls parallel to the pullMore tool cost, a witness line, maintenance
LifterInternal snap hooks and inward lipsCoupled to the ejector plate; moves at an angle as the part is pushed outInternal undercuts that a slide cannot reachClears only a few millimeters; needs free space inside the part; wears
Collapsible coreInternal threads and internal rings around a round coreSegments collapse inward when the center pin withdrawsCaps, closures and round internal featuresSpecialized purchased component; size limits; segment witness lines
Unscrewing coreInternal or external threadsCore rotates to back the part off the threadHigh-volume threaded closuresMost complex and costly option; the part needs anti-rotation features
Bumpoff (stripping)Shallow, rounded undercuts, including shallow threadsA stripper plate or ring pushes the part, which flexes over the steelPP, PE, TPE and TPUOnly works for shallow, radiused features
Telescoping shutoffHooks and clips with a window under themNo side motion: steel from one half passes through the part to meet the otherSnap hooks designed with a pass-through openingNeeds draft on shutoff faces; leaves an opening
Hand-loaded insert or secondary operationAny feature at low volumeAn insert is ejected with the part and removed by hand, or the feature is drilled or milled after moldingPrototypes and low volumesAdds cycle time or labor per part

Slides, or side actions

A slide is a block of steel that forms a feature from the side. On simple tools an angled pin fixed in the stationary half drives the slide outward as the mold opens; a locking heel holds it shut against injection pressure. When the travel is long, the slide has to retract before the mold opens, or the slide sits on the stationary half, a hydraulic cylinder moves it instead; it still needs a locking heel, or a cylinder sized to hold the injection load, and limit switches to confirm its position. Slides are the standard answer for connector openings, side holes, external clips and hose barbs.

Lifters

A lifter is an angled core coupled to the ejector plate through a sliding or pivoting foot, so as the ejectors push the part forward the lifter also moves sideways and slips out from under an internal hook. Its sideways travel equals the ejector stroke times the tangent of the lifter angle, so a lifter usually clears only a few millimeters. Lifters are the usual answer for an internal snap hook that has no window under it. The part needs empty space inside next to the feature for the lifter to move into, which is a design constraint worth checking early.

Two section drawings of a closed injection mold at the same scale. Left: a slide whose nose forms a 3 mm deep hole in the part wall, driven by an 18 degree angle pin that stays engaged for 24 mm of opening, so it travels 7.8 mm, and held shut by a heel block wedged at 20 degrees. Right: a lifter at 7 degrees that forms a 1.5 mm internal snap hook and moves 3.1 mm inward during a 25 mm ejection stroke, with its foot held in a T-slot on the ejector plate
Same scale, mold closed. Both travels come from the angle: the opening while the pin is engaged, or the ejector stroke, times its tangent.

Collapsible and unscrewing cores

Shallow, rounded internal threads in PP or PE are routinely stripped off a solid core with a stripper ring. Deep or sharp threads, and threads in stiffer resins, cannot be. For those, a collapsible core is made of segments that collapse inward when its center pin withdraws, and a stripper ring then pushes the part off; the segment joints leave witness lines. An unscrewing core rotates the thread out, driven by a motor, a rack or a hydraulic unit, and the part needs ribs, knurls or stripper teeth so it does not spin with the core. Both are specialized, and for low volumes a threaded metal insert or a self-tapping screw boss is often the better design. Our plastic part design guidelines cover bosses and inserts.

Six white molded polypropylene screw caps on a steel workbench, three upright showing the ribbed outer wall and three open side up showing the internal thread and a small gate mark in the center
Caps like these are molded on unscrewing cores or, when the thread is shallow and rounded, stripped off a solid core.

Bumpoffs and stripped undercuts

If the undercut is shallow and rounded and the resin is flexible, the part can be pushed off the steel and spring back. A stripper plate or ring pushes the part evenly so it is not marked or torn. This works with PP, PE, TPE and TPU; it is a poor fit for stiff resins like polycarbonate or glass-filled nylon, which crack or whiten instead of flexing.

Telescoping shutoffs

A snap hook can often be molded with no moving steel at all if the wall under the hook has a window. Steel from one mold half reaches through that window to form the underside of the hook and meets the other half; the part pulls straight off. Protolabs recommends at least 3 degrees of draft on those shutoff faces to avoid steel rubbing on steel, flash and tool damage; production steel tools often use more.

How to design undercuts out of a part

The cheapest action is the one that is never built. Before accepting a slide or lifter, check whether the part can change instead:

  1. Move the parting line. A side hole or barb that sits on the parting line can be formed by the two halves meeting, with no action. A stepped parting line can catch several features at once. Watch sealing and cosmetic edges: on a barb, the parting line crosses the sealing ridge, and any flash there becomes a leak path.
  2. Open the feature to an edge. A closed side hole needs a slide; a slot that opens to the rim of the part often does not.
  3. Give snap hooks a window. A hook with a pass-through opening under it can be molded with a telescoping shutoff instead of a lifter.
  4. Group side features on one face. Connector openings on the same wall can share one slide; spread over three walls they need three.
  5. Change the fastening. Screws into bosses, threaded inserts or ultrasonic welding can replace an internal thread or a hard-to-release latch.
  6. Make a small part carry the difficult feature. When one feature drives the whole tool, molding it as a separate small part and assembling it can cost less than adding actions to the large mold.
  7. Machine it at low volume. For prototypes and short runs, drilling a hole after molding can be cheaper than a slide. Soft tooling is a good place to test that.
Decision flowchart titled Before you accept a slide or a lifter, with five questions in order: can the parting line or pull direction change so an outside feature pulls straight; can the hole open to an edge or the snap hook get a window; can a screw, insert or separate part carry the feature; is it shallow and rounded in PP, PE, TPE or TPU so it can be stripped; is the volume low enough for a hand-loaded insert or machining; otherwise the mold needs moving steel: usually a slide outside, a lifter inside, or a collapsible or unscrewing core for threads
Work down the list. Moving steel is the last answer, not the first.

Three common enclosure cases

These are typical patterns on electronics housings and how the mold usually handles them.

A wearable with side connectors and internal snaps

USB-C and charging openings closed on all sides are formed by slides. Splitting a port between the two shells at their mating edge removes that slide, since each shell then forms half the opening with a straight pull and a drafted shutoff. The shell seam then crosses the port, so mismatch between the two shells affects the connector fit. Internal snap hooks are released by lifters, or by shutoffs if the hooks get windows.

A handheld device with internal latches and a textured grip

Lifters form the internal latches for tool-less assembly. The textured grip is not an undercut, but texture behaves like many tiny ones, so textured walls need more draft than polished walls; texture suppliers publish the minimum draft for each texture depth. Our surface finish guide covers texture and draft.

An industrial sensor housing with several cable ports

Several ports on different walls mean several slides. Moving them to one or two walls, or onto the parting line, can cut the action count. Many cable glands mount with a locknut through a plain hole, which needs only a slide. A threaded port puts an unscrewing or collapsible core inside the slide, so a molded-in or pressed metal insert is often the simpler answer.

How to find undercuts in your CAD

  • Set the pull direction first. An undercut only exists relative to it.
  • Run a draft analysis from that direction to flag faces with too little draft, and an undercut analysis to flag faces that are trapped in both directions. SOLIDWORKS has a dedicated undercut analysis tool, and most CAD packages offer draft analysis.
  • List every undercut and tag it must keep, negotiable or remove.
  • Ask the molder for an action count, and which feature drives each action, before the CAD is frozen.
  • Run a mold flow simulation to place gates. Openings create weld lines however they are formed, and gates should stay off slides and lifters, which are also hard to cool.

What to include in an RFQ for a part with undercuts

  • 3D CAD, preferably STEP, with the intended pull direction if you have one.
  • Which undercuts are functional and which could change.
  • Cosmetic surfaces where witness lines are not acceptable.
  • Resin, since flexible and stiff resins allow different release methods.
  • Annual volume and expected tool life, which decide between hand inserts, slides and unscrewing cores.
  • Critical dimensions on features formed by actions.

Expected volume also decides the tool material. See aluminum vs steel tooling for how actions and wear interact with each.

Why one team for design, electronics and molding helps

On an electronics product, undercuts are rarely only a molding question. Connector positions come from the PCB layout, snap-fits come from the assembly sequence, and keep-out zones decide where bosses and ribs can go. When product design, PCB layout, injection molding and final assembly are reviewed together, a connector can move to the parting line before it becomes a slide, and a snap-fit can be shaped for the mold before the tool is quoted.

Common questions about undercuts

What is an undercut in injection molding?

A feature that prevents the part from being ejected straight out of the mold along its opening direction, such as a side hole, a snap hook or a thread. It needs a moving mold component, a flexible resin or a design change.

Do undercuts make a mold more expensive?

Yes. Each slide, lifter or rotating core adds machined parts, fitting and tryout time, a larger mold base in some cases, and ongoing maintenance. The number of actions is one of the main reasons similar-sized parts get very different tooling quotes.

What is the difference between a slide and a lifter?

A slide usually forms features on the outside of the part and moves sideways, driven by an angle pin or a hydraulic cylinder. A lifter usually forms features on the inside; it is coupled to the ejector plate and moves at an angle as the part is ejected.

Can a part with undercuts be molded without side actions?

Often. Moving the parting line, opening a hole to an edge, adding a window under a snap hook for a telescoping shutoff, or stripping a shallow undercut off the steel in a flexible resin all avoid side actions.

When is an unscrewing mold worth it?

When a threaded part runs at high volume, the thread is too deep or sharp to strip, and it cannot be replaced by an insert or a screw boss. An external thread can often be split along the parting line instead, usually with small flats where the halves meet. At low volume the extra tool cost of unscrewing is hard to recover.

Key takeaways

  • An undercut is any feature that blocks straight ejection along the pull direction.
  • Slides usually handle outside features, lifters inside features, and stripping, collapsible or unscrewing cores handle internal threads.
  • Every action adds cost, lead time and maintenance, and most leave a witness line.
  • Parting line changes, edge openings, windows under hooks and grouped features remove many actions.
  • Ask for the action count during DFM, before the CAD is frozen.

Have a part with snap-fits, side ports or threads? Upload your CAD for a quote. Every quote includes a DFM review, and our engineers can tell you which undercuts need actions and which design changes remove them before steel is cut. For a checklist to use on your own designs, get the injection molding design kit.

Related reading